OPA828: Gain error of the voltage follower with OPA828

I simulated in Spice the complex open loop gain of both amps. At 10 MHz the phase shift is ca. -98 deg for OPA827 and -220 deg  (!) for OPA828.

The open loop gain characteristics presented on the 1st page of the OPA828 datasheet show approximately -95 deg at 10MHz.

Something is wrong with the Spice model or I am doing something wrong?

Regards,

Marian

Hi Marian,

TINA-TI shows a deviation of only 44ppm at 1MHz:

marian_opa828.TSC

Kai

Hi Kai,

That's a good news.Thank you!

I am using LTSpice and your Spice model. Could you advice how to correct this model?

Best regards,

Marian

Hi Marian,

I am using LTSpice and your Spice model. Could you advice how to correct this model?

I do not see issues with OPAx828.LIB that I downloaded from the following website. 

https://www.ti.com/product/OPA828#design-development##design-tools-simulation

I duplicated the same simulation as Kai's schematic in LTSpice, the measurement is exactly identical at 1.0MHz. 

At 1.0MHz, LTSpice is measured -380.78144udB or 10^(-380.78144udB/20)=0.999956161 in gain, which is 43.84ppm in deviation. 

If you need further assistant, please let me know.

Best,

Raymond

Dear Raymond,

Thank you!

I found the error in my simulation: the .options cshunt = 1e-14 was the reason.

But I see another problem: what gain error at low frequencies (<100 Hz) do you get? I am getting 1.7 ppm even when using the alternate solver.

Best regards,

Marian

Hi Marian,

I run the same simulation from 1Hz to 10MHz (LTSpice), the frequency response is "flat" from 1Hz to 400kHz. 

For example, at 10Hz, the gain is measured at 14.570343udB or 1.000001677 or 1.678ppm, which is the same as yours. 

If you have additional questions, please let us know.

Best,

Raymond

Hi Raymond,

Thank you.

Where does this ca. 1. 7 ppm come from? It should be zero. I played with various controls of the LTSpice simulator and it is still there.

We are designing very precise measuring instruments so this 1.7 ppm is high for us.

Best regards,

Marian

Hi Marian,

It is probably related to Aol and internal bias current inside of op amp design. What are your gain errors requirements per your application? Please provide us the frequency operating range, gains, load requirements and operating temperature that are used in the application.  

Best,

Raymond

Hi Raymond,

The gain error of the follower should be within +-1 ppm from DC to 100 kHz at ambient temperature 20 - 40 deg C and 10 kohm load.

Best regards,

Marian

Hi Marian,

1.7ppm is too high an error for you? :-)

1ppm is 0.0001%. Even ultra-ultra-precision foil resistors offer a TCR of more than 0.14 ppm/°C, a tolerance of more than ±0.005% and a long-term stability (1 year) more than 25 ppm.

Kai

Dear Kai,

AC voltage standards, which we had developed have AC-DC transfer difference below 1 ppm between ca. 100 Hz - 10 kHz.

We are able to compare them with ca. 0.3 ppm standard uncertainty,

Please take a look at my publications in IEEE Transactions on Instrumentation and Measurement: ieeexplore.ieee.org/.../searchresult.jsp

Anyway, the voltage follower circuit does not contain any external resistor.

Moreoover, with ca. 140 dB open loop gain at DC the OPA828 should in theory have sub-ppm gain error at frequency well below the first pole, but it shows there the 1.7 ppm.

If the reason of the 1.7 ppm is the CMRR then it should somehow depend on frequency, but it does not.

And it is AC analysis, so the op-amp offset voltage and other DC parameters should not affect the AC gain error.

Maybe LTSpice is giving bad results. Maybe...

Regards,

Marian

Hi Raymond,

This explains the error. Indeed, the simulation model includes the CMRR vs. frequency  effect.

The cure could be bootstrapping the power supply of the op-amp so the ground would follow the input signal. I will check this.

Thank you very much.

Best regards,

Marian