This thread has been locked.
If you have a related question, please click the "Ask a related question" button in the top right corner. The newly created question will be automatically linked to this question.
Part Number: OPA2209
I was using Tina TI to build a filter circuit using the OPA2209. I used the macro in the Tina library and my circuit was working fine. I was on line and I noticed a new PSpice file for the OPA2209 called OPA209. I downloaded the file and imported the Macro. Now when I analyze my circuit (transient analysis), it has a 1.5vdc offset (not good). So, I my question is, did I do something bad when I imported the file? Also, when I used the Macro, it came up with an error in which the very last line had a ".P" in it. Tina, did not like that apparently, so I made it a comment. After I did that, the macro came to life and I could analyze my circuit.
I did this with several op amps. If I use the one in the library, it works. If I use the PSpice model you provide and import it, I get the error and the offset. What am I doing wrong.
Sorry you ran into a problem with our OPA209 simulation model. The first model that you mention is an older, but well vetted OPA209/OPA2209 simulation model that was released sometime in the 2010 timeframe. It has been included in the TINA-TI op amp selection for a long time and should provide you with accurate filter response. The OPA209 model retrieved from the web page is a newer, 2019 version of the model that provides additional enhancements. Unfortunately, in some cases a few bugs have found their way into some of the revised models.
I would go ahead and use the OPA2209 model provided with TINA-TI. You should see good simulation results from it. If you want to send me your TINA circuit file that uses the newer OPA209 model version, I can try and replicate the problem your are seeing when you attempt a transient analysis. If I can replicate the problem, I can file a bug report and have it added to the model repair queue.
Precision Amplifiers Applications Engineering
We are glad that we were able to resolve this issue, and will now proceed to close this thread.
If you have further questions related to this thread, you may click "Ask a related question" below. The newly created question will be automatically linked to this question.
In reply to Thomas Kuehl:
Filter Circuit.TSCHere are my files. Filter Circuit macro import.TSC
In reply to Glenn Varnon52:
Thank you for providing your OPA2209 TINA schematic. That allowed me to run some simulations and gain some perspective into the problem you observed.
When I take your ground fault filter circuit which had a dc input battery of +300 mV and replace with a dc voltage source that could be swept from 0 V to a higher positive voltage an interesting difference was observed between the original TINA-TI OPA2209 model and the newer website OPA209 models. You can see the results of the sweeps here:
Observe that in the righthand image the OPA2209 model output begins to change with the dc input level as low as about +175 mV. The output begins to go nonlinear with an input level of +2.3 V. By comparison, the newer webpage OPA209 output doesn't begin to change until the input voltage is +1.5 V and then continues to follow at least to +3.7 V as the graph shows.
This points out an important issue with your circuit. The OPA209/OPA2209 common-mode input voltage (VCM) range is specified as (V–) + 1.5 to (V+) – 1.5 V. Since you have the V- supply in your circuit set to ground, or 0 V, the minimum VCM is +1.5 V; the same voltage that is received from the newer webpage OPA209 model. Therefore, it appears that the older TINA-TI OPA2209 model is not providing correct common-mode behavior.
If you are to use the newer OPA209 model and operating it within the correct VCM range, I do expect it would provide your with correct filter response. I ran an ac sweep with a 2.5 V dc source included in series with an ac input source.I obtained the following low-pass amplitude responses with SW-SPST2 opened and closed. I expect the responses are correct for the component values used in the filter.
Do use the newer webpage OPA209 simulation model for your analysis.
All content and materials on this site are provided "as is". TI and its respective suppliers and providers of content make no representations about the suitability of these materials for any purpose and disclaim all warranties and conditions with regard to these materials, including but not limited to all implied warranties and conditions of merchantability, fitness for a particular purpose, title and non-infringement of any third party intellectual property right. No license, either express or implied, by estoppel or otherwise, is granted by TI. Use of the information on this site may require a license from a third party, or a license from TI.
TI is a global semiconductor design and manufacturing company. Innovate with 100,000+ analog ICs andembedded processors, along with software, tools and the industry’s largest sales/support staff.